Tool Library
At a glance
- Edit → Tool Library—tools stored on the machine .jcm profile for Router, Mill, and Lathe
- Flat, ball, bullnose, drill, engrave, and chamfer cutter types with type-specific geometry tabs
- Surface speed drives spindle RPM; feed per tooth drives cutting and lead feeds; plunge feed linked to plunge per rev
- Chamfer mill included and chamfer angles stay linked when you edit included angle or chamfer angle
The Tool Library lives at Edit → Tool Library… and stores tools on the owning machine's .jcm
profile, so a library travels with the machine and is shared across Router, Mill, and Lathe work.
Every operation's Tool tab also has a Tool Library… shortcut beside the Selected Tool dropdown
— add or edit a cutter mid-setup and the dropdown refreshes in place.
Tool types and geometry
Each tool has General (name, number, coolant, notes), Cutter, and Feed & Speeds tabs. The Cutter tab adapts to the type: drills store an included point angle (default 118°), ball endmills show a derived ball radius of half the diameter, bullnose endmills store their corner radius, engrave endmills store tip radius and included angle, and chamfer mills store an end diameter plus linked angles — edit the included angle and the chamfer angle becomes half of it, and vice versa. Every type carries flute count and spindle cutting direction (CW/CCW).
Linked feeds and speeds
The feed/speed fields are coupled the way you actually calculate them. Surface Speed (SFM) and Spindle Speed (RPM) drive each other through the tool diameter; Feed Per Tooth × flutes × RPM drives the Cutting Feedrate (and vice versa); Plunge Feedrate stays linked to Plunge Feed Per Revolution. Change the diameter or flute count and the dependent rates recalculate. Lead in/out and ramp feedrates, ramp angle, and a ramp spindle speed round out the record — all of which copy onto an operation when you select the tool, then remain editable per operation.
Which operations take which tools
Contour, Bore, and Pocket accept flat, ball, and bullnose endmills. Drill adds dedicated drill tools to that list. Chamfer requires a chamfer mill, and Engrave takes engrave endmills, chamfer mills, or any regular endmill.